Description🔗

The nutkRoughWallFunction is boundary condition that provides a wall-function for the turbulent viscosity (i.e. nut) when using wall functions for rough walls, based on the turbulent kinetic energy (i.e. k). The condition manipulates the wall roughness parameter (i.e. E) to account for roughness effects.

Parameter ranges: - Roughness height (i.e. Ks)= sand-grain roughness (0 for smooth walls) - Roughness constant (i.e. Cs) = 0.5-1.0.

Usage🔗

The condition requires entries in both the boundary and field files.

Boundary file🔗

<patchName>
{
    type            wall;
    ...
}

Field file🔗

<patchName>
{
    // Mandatory entries
    type            nutkRoughWallFunction;
    Ks              <scalarField>;
    Cs              <scalarField>;

    // Inherited entries
    ...
}

where:

The inherited entries are elaborated in:

• nutkWallFunctionFvPatchScalarField.H

Further information🔗

Tutorial:

• $FOAM_TUTORIALS/multiphase/interFoam/laminar/damBreakWithObstacle

Source code:

• $FOAM_SRC/TurbulenceModels/turbulenceModels/derivedFvPatchFields/wallFunctions/nutWallFunctions/nutkRoughWallFunction

API:

• Foam::nutkRoughWallFunctionFvPatchScalarField

History:

• Introduced in version 2.4.0